The Autodesk Inventor Default Setting From Hell

If you want to save yourself a huge amount of grief, there is a default setting in Autodesk Inventor that you should change immediately! The setting in question is the Parallel and perpendicular constraint for Constraint placement priority.

By default, Autodesk Inventor sets the constraint as mentioned above, to Parallel and perpendicular (as seen in the image to the right) as opposed to Horizontal and vertical –the other choice in the Application Options. This default setting can screw you up big time –but it all depends on what you design. We’ll get into that a bit more later, and I hope others will weigh in the comments  as to why they have the setting from hell enabled.

My first run-in with this setting happened while creating a three dimensional floor plan for a yacht I was working on (now called Ingot –back then it was Hull 503). Basically I was designing four stacked decks ranging in length from 150’ for the main deck to 30 feet or so for the fly bridge. It was a huge improvement over the previous designs created in AutoCAD in many ways, but a nightmare in others.

The two biggest problems were the default Parallel and perpendicular setting and Inventor sketches running out of steam (more about this in a later post, but basically once you get to a certain point in a sketch, the program will bog down and your sketch will become very buggy). You can easily solve the first one –the second requires a lot of experience to work around it. But before you just go ahead and change the setting, let me show you what can happen.

 

 

 

 

The problem boils down to design intent. When creating a layout for a plant floor or, as In my case, a yacht floor plan, when I draw a line vertically, I expect the line to stay vertical. Which is what you get when the constraint priority is set to Horizontal and vertical. Not so with the Parallel and perpendicular. This setting applies a Perpendicular Constraint to the last line drawn in the same orientation!

 

 

 

 

In the image to the left, a line was drawn from the projected Center Point upwards—– a Vertical Constraint was added automatically by clicking while the Vertical Constraint Glyph was visible.  

 

 

 

 

I then drew six more lines, five to the right and one to the left –which can be seen in progress in the image below. Notice the inferred constraint glyph is to place a Parallel Constraint between the new line and the last line –which happens to be on the other side of the sketch…

 

I can change the inference simple enough by scrubbing a different line…

 

…and then clicking to accept that constraint, but for the purpose of this demonstration, I just let the last line on the left be constrained to the one on the right…

 

We now have seven lines that are constrained vertically via a daisy chain constraint. Right click in the sketch and choose Show All degrees of Freedom from the Context Menu. The degrees of freedom shows that the original line will be fully constrained with one more constraint on its length. The rest are free to move about in any direction except rotational –because they are constrained vertically via the daisy chain back to the original line…

 

 

Right click again and choose Show All Constraints…

 

Now hover your mouse over the individual constraints. If you hover over the Vertical Constraint on the first line, the line and the constraint will highlight. Now hover over one of the Parallel Constraints on one of the middle lines. Notice how the line that the constraint is on, the previous or next line, and both constraints are highlighted (lines turn red)…

 

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